CHANGING PART REF IN VIEWS

[nitan]

You guys are so helpful.


I have a 2 drawings to do. The only difference is .250" in length, and all of the other dims are the same. I used the 1st drawing as the template for the 2nd, but the views are referencing the original part. How can I change the reference of the views to the new part and keep the dims, and will they work with the new part? It seems that if I had the new part in the tree it would work, but is that the answer. I can set new part to the current drawing, but that doesn't fix the views.


Any help would be appreciated.

 

[appinmi]

First thing is to set the config.pro option rename_drawings_with_object to BOTH. Make sure that the drawing file has the same name as the part file, (ex: mypart.prt.2 and mypart.drw.4). Now call up the first model, (not the drawing), and do a "Save As". Give it the new part filename. Proe will create a new part file and a new drawing file that is dependent on the new part.Call up the new drawing file, make your changes, and save.

 

[Isair]

Yes but if parts are the same except in only one dimension, then is a lot more easier, and elegant to create family able of part, put this different dimension in instance.
Then open drawing of first part, replace first part with instance, and whole drawing remain with all dimensions, surf finish notes etc, and your different dimension is also changed (if you have create dimensions using Show/Erase).
After that just Save As drawing with different name and you are done

 

[nitan]

Hi,


I reset the config.pro to both, and renamed the model file, but no new drawing file appeared. Is there a setting that I missed? The instant thing sounds good too, but not sure how to do it.


I am using Pro-E Wildfire, there is no "Save As", just "Save A Copy". Probably the same thing.


Thanks

 

[dr_gallup]

Rename_drawings_with_object only works if both the drawing and the object are named exactly the same. We never name drawings and objects the same so it does not work for us. Family table instance is very simple. Choose one part as the generic. Click Tools/Family table. Pick Insert Columns. Pick the feature containg the variable dimension then the dimension itself. Click OK. Pick the generic instance name in the table, hit enter, You will get an new row. Change the name of the instance, change the value of the variable dimension. Pick open and your new part instance will open in it's own window. Go the the drawing of the generic part, rename it. BE SURE TO CLICK THE "IN SESSION" check box so you don't chage the name of the original drawing on disk. Right click in the drawing, select properties/drawing models/Replace. Pick your new instance. Save your new drawing.

 

[nitan]

YOU ARE THE MAN!!


It worked like I knew it had to. Saved me several hours of work.


Thanks.

 

[nitan]

Ok, now I need to revise both of the drawings with new dimensions.


When I change the model, the dims in the drawing don't update. What could the problem be?