CONVERTING PROE WF2 MODEL TO PROE2001

[ARUN KUMARM]

hello users


how can a model in pro e wildfire 2 version be opened in pro e 2001


if there is no direct method, how can it be opened in pro e 2001


what is the best export file format for pro e files like STEP, IGES, SAT,...


i want the pro e wildfire 2 model to be transferred to pro e 2001 version with all the features recognized as in the wf2 model


i want all the features like EXTRUDE, CUT , REVOLVE , SHELL , etc.. as done in the original model


how can i do this


can anyone help me to solve this problem


ARUN KUMAR.M

 

[erikmjuntunen]

Is there an option to save it as a version 2001 inside Wildfire? I'm not sure if your requirement of still having all the features identical is possible.

 

[puppet]

heheh i love that question

i think everyone has asked it or wondered about it.





step is the best way to convert. but you will not be able to see features like.

-cuts

-shells..

etc

you just get a soild.



if you find a way. there will probably be lots of very happy people on this forum

 

[dacct]

PTC recommands to tranfer files from WF1 (don't think this would have change in WF2)to 2001 via .neu format. It works well but only the geometry data is tranfered and will show as a plain solid in 2001...


Check your online doc for "data exchange between pro/engineer releases".

 

[phoxeoy]

Can you open the file in Pro/Desktop save it as a .sec file and then open it in 2001?

 

[JayKM]

Hi All,


I had the same question answered just 2 days back in PTC/Users discussion. The best way to handle this is to use Neutral File formats. I have 2 PDF files that deal with this that I would be happy to share. Please mail me at [email protected] if interested.


Secondly, it is possible to convert pro/e models in newer versions to older versions.


Check the website http://www.fawcett.com/ that contains several tips and tricks, including a way to convert2001 files to 2000i^2. [ you'd need to register first- a matter of minutes]
<DIV>I am not sure about WF2, but if it works for 2001-->2000i^2, it might work for WF2 as well!</DIV>
<DIV></DIV>
<DIV>Regards,</DIV>
<DIV>Jay</DIV>

 

[gurveen]

I have this explaination for converting from 2001 to 2000i2


1. Open Pro/E 2001 with the part you wish to convert.
2. Select Feature/UDF Library/Create You will be prompted to give the gph file a name.
3. Select Stand Alone and then No when asked if you should include the reference part.
4. Select all the features from the model tree except the 3 default datum planes
5. You will now be prompted to enter names for your references and to specify whether you should only be prompted
once or multiple times for each references. Be Sure to select Single for each reference and also name the references
according to what each datum is named. ie. DTM1, DTM2, XPlane, Front, Top, etc.
6. Next you will be prompted to review your references and prompt names. If satisfied, click Done
7. Open Pro/E 2000i2 and follow the same procedure with a dummy file. Give the udf a different name. You can skip this
step by downloading a text file of the needed udf information by right-clicking here
8. Open both files in Notepad and cut/paste from the 2000i2 (or downloaded) file header into the 2001 file. Be sure to
replace the entire string of information that you find in the above downloadable file.
9. In 2000i2, create a new part that contains only the 3 default datum planes.
10. In 2000i2, select Feature/Group and browse to find the edited gph file.
11. Select Independent, Same Dims, and Normal for the display of invariable dimensions.
12. Select 3 datum references as prompted and then select their direction.
13. Click Done
You will now have your 20001 part imported into 2000i2.


You can right click on the group name in the model tree and select Ungroup to break it apart into the features

 

[Guest]