dimension dementia

[tbird6391]

<DIV>got a question for you</DIV>
<DIV></DIV>
<DIV>have a 2 sheet drawing, with dimensioned views of a model on the 1st sheet and a table on the second sheet.</DIV>
<DIV></DIV>
<DIV>If I puta dimension name ina table cell (i.e. &add32) it displays the dimension fine in the table but removes it from the view. It will show up in the viewif removed from the table.</DIV>
<DIV></DIV>
<DIV>how to keep it from disappearing ?</DIV>
<DIV>thanks</DIV>
<DIV>rick</DIV>

 

[ankarl]

Not 100% sure here but I think you can bring it back by using "show" again after using the dim in a note or table.
Have done it before so I know its possible.

 

[tbird6391]

nah, nothing seems to work.. it's in the documentation that it is SUPPOSED to do that. show wont even pick it up... like it doesnt exist.


I'm trying to find a work-around, like assign the dimension value to a user variable then post the variable to the table. Know how to do that?

 

[contour]

CREATE NOTE&add32 ANYWHERE IN DRAWING


CREATE SECOND NOTE &add32 WHERE YOU NEED IT


DELETE FIRST NOTE.

 

[tbird6391]

thanks contour it worked (in wildfire)


hope that is not a bug they intend to fix.


just for curiosity tho anybody know how to do it with parameter assignments.. just wondering


thanks

 

[donha]

To use a parameter:
1. Find the dimension you want to represent, eg. d20
2. Create a parameter, eg. LENGTH or simply create a relation LENGTH=D20
3. Add the parameter LENGTH=D20
4. Show the dimension on the print and add &LENGTH to your note


The reason the dimension dissapears from the drawing is the drafting standard of not displaying duplicate dimensions on a print. It is not a bug, it is standard drafting practice.