dimesion to edge parallel to sketchplane

[yelloeng]

I'm trying to put dimensions on a revolve so that I can pattern it and have each patterned object move in increments in the x and y directions at the same time. I'm trying to do it as shown in this tutorial on the ptc site. My problem is that I'm a newbie and can't figure out how to get dimensions in the x and y directions because in the sketcher I cannot dimension to an edge or plane that is parallel to my sketching plane. I'm not sure if this is something I'm suppose to do outside of sketcher. I cannot figure out how they did it for the video. I'm using wildfire 5, if that is relevant. The red marks in the pic that I have attached are the dimensions that I would like to have, but I can only get one or the other depending on what the sketch plane is parallel to. Any help you guys could give would be much appreciated.


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Edited by: yelloeng

 

[Bob_W]

This is the second response

I forgot to copy it before I hit post reply and I entered the captcha wrong and erased my text!

Probably several ways to do this but here is one:


1 - Create an axis on the top surface and use the sides indicated by you red dimensions to locate the axis on the top surface. The axis should be perpendicular to the top surface.

2 - Pattern the axis as required.

3 - Start the revolve feature and when asked for the sketching plane create a new one that passes through your first axis and is parallel to one of your side surfaces. If I create the sketch plane first (in WF4) the pattern will not increment in two directions at once.

4 - Once in the sketcher set the first axis as a reference and sketch an axis of revolution through it.

5 - Complete your revolved sketch and exit

6 - Reference pattern your feature.

This should work for you.

Bob

 

[Bob_W]

yellowen:

I didn't look at the tutorial until after I posted the above response. For what they are doing, you need to follow slightly different procedure:

1 - Start the revolve feature. When asked for the sketching plane create one offset from one of your surfaces. Then for the next sketcher reference plane create another one offset from your other surface.

2 - click sketch and create your revolved feature.

3 - Pattern the feature. All of your dimensions should now show up when you pattern the feature so you can complete the tutorial.


I use the previous method for pattern tables, this is the easiest for your tutorial.

Bob

 

[jraquet]

Youshould be able topattern by direction rather than dimension and use the reference eges/faces you are dimensioning to as directional references.

 

[yelloeng]

Thank you both for your answers.
Bob_W, you solution worked perfectly, I never would have
thought to create the planes after starting the revolve
instead of before it. Thanks!