Flipping chamfer attachment

[skraba]

I'm not sure is it possible to change chamfer dimension attachment fromhorizontal to vertical or vice versa. I have the following drawing (see below) and want the chamfer dimension 2x45 to be shown as vertical dimension not horizontal. I know the workaround would be creating AnglexD chamfer and then flipping the side, but that's not what I want. Is there any drawing setup option or command that I don't know of?


View attachment 1467

 

[appinmi]

Change your chamfer from "D x D" to "D1 x D2", set both dimensions the same. When in drawing, it will show both dimensions. Just keep the one you want and add the "2X" to the dimension text.

 

[Dell_Boy]

Have you actually created the chamfer as a true chamfer or just sketched it in the section. The reason I ask is that my chamfers automatically show up in note style


View attachment 1469


which is far more flexible to position


DB

 

[skraba]

I have actually created it, with option DxD. As to D1xD2, with that you have to type two dimensions and still change dimension text to 2x45. So I don't achieve anything and is still better to create drawing dimension and drive the chamfer from the model.

 

[phoxeoy]

Dell boy, how do you get the chamfers to show with one leader line. I can't find that option anywhere in wf2.

 

[phoxeoy]

I would also like to know if anybody has found a way to switch the side
that a horizontal chamfer dimension shows on a diameter. Thanks

 

[dr_gallup]

Dell boy, how do you get the chamfers to show with one leader line. I can't find that option anywhere in wf2.

Set this in your .dtl file:
chamfer_45deg_leader_style std_asme_ansi

You can also edit attachment to move to other side of circle.

 

[phoxeoy]

I've tried edit attachment and that does not move the dimension to the other side. Am I doing something wrong? thanks

 

[Dell_Boy]

Dr Gallup,

the chamfer_45deg_leader_style option is listed in the help system but
cannot be found from within Pro/E using Tools/Options so I wasn't sure
if it still relevant. Is this a hidden setting or one that PTC has lost
somewhere along the way.





Phoxeoy,

I have chamfer_45deg_dim_text set to iso/din and no setting for
chamfer_45deg_leader_style so I can only assume it is taking the
default std_asme_ansi.





Edit attachment should allow you to move chamfer dimensions to other locations. Try again.







DB

 

[dr_gallup]

Dr Gallup,
the chamfer_45deg_leader_style option is listed in the help system but
cannot be found from within Pro/E using Tools/Options so I wasn't sure
if it still relevant. Is this a hidden setting or one that PTC has lost
somewhere along the way.

DB

It is a drawing detail (.dtl) file setting, not config.pro setting.

 

[taik]

Dr Gallup,
the chamfer_45deg_leader_style option is listed in the help system but
cannot be found from within Pro/E using Tools/Options so I wasn't sure
if it still relevant. Is this a hidden setting or one that PTC has lost
somewhere along the way.

DB

It is a drawing detail (.dtl) file setting, not config.pro setting.

Yes, you can edit it in 2D drawing. Right click the mouse, click "Properties"-->"Drawing Options". Remember to save it after you revising it.