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Hidden Lines Displayed

K

kerklein2

New member
I imported a model from a manufacturers website and it appears that most of the geometry imported as cosmetic features because the wireframe is that purple color and when I try to use the hidden lines not displayed display mode, they are still displayed. Is there anyway to convert these so that I can get a normal hidden line mode? I am trying to create an assembly drawing and I would like it to be hidden. I have attached the assembly.

Also, I tried creating a shrinkwrap, but that did not work either.



2008-11-24_130208_southco_hinge.asm.zip
 
> attached the assembly


Pro/E Version?


It sounds like what you're thinking of as 'cosmetic' is, in fact,
open surfaces or quilts. (purple = magenta?)


Link to the original downloaded file?
(How big? I may not want to fiddle with it on a slow DUN.)


You are aware that there are HLR for quilt options?


> Also, I tried creating a shrinkwrap, but that did not work either.


I'm afraid to ask.
smiley1.gif
 
I seem to have found the HLR options under component display and tried selecting a component and switching it to "no hidden" but that did nothing. I also just realized I have a couple screws I imported from McMaster that are doing the same thing.
 
Is SW3dPS-E6-10-212-50.zip what you downloaded from SouthCo?
I'm going to have to scratch my head over that one. Its
Granite neutrals but acts a little strange....


Anyway,



2008-11-24_151310_solids--wf2--.zip


is your original 2008-11-24_130208_southco_hinge.asm.zip
cleaned up a little and in Solid form. I'm not sure how
you might integrate it... maybe backup everything you have
(just in case) and try overwriting or replacing your
existing model files.
 
Thanks jeff. Yes, the second .zip I linked was directly off the southco website. Can you mind giving me some insight into what you did to the model?
 
Very basically, I changed to .01 mm abs acc on a few of them
which fixed a couple of problems and caused one or two more to
show up (as changing accuracy often does), cleaned up a few
'broken up' edges (heal geometry - manual - edit boundary -
merge edges), zipped gaps on a few. Only one seam edge really
proved problematic and that was a simple fix by creating an
untrimmed copy of one of the surfaces, deleting the original,
return to model mode and Extend all boundaries so it overlapped
the trim boundary edges, then trimming it. Return to Import
Feature Edit mode and Collapsed the newly trimmed surface
into the quilt.


That's the simple explanation. ;^)

Sorry, I don't have to go into detail. It's a subject that could
stand a Lot of discussion though. Documentation is pretty scarce
re geometry 'healing' and good explanations require going well
beyond program specific 'button recognition' to get a handle on it.
 
I've found with SouthCo models, importing the IGES or STEP is better then the Pro|E. The Pro|E is just an import anyway.

HLR for quilts is a setting in your drawing view properties that might fix it for the drawing without actually repairing the open quilts.
 
> I've found with SouthCo models, importing the IGES or STEP
> is better then the Pro|E. The Pro|E is just an import anyway.


Good point, Doug. The last few years have seen the emergence of
a Native Format Fad among low end (oh! lookie, I can open ...)
developers. The big ASSuption is that the geometry is cleaner,
more robust than the neutral standards. It Ain't always so.


kerklein,


You gonna have to quit picking up stray junk on the 'net.
Look thru the files section here and scour the 'net for
some good table driven parts. There's lots around.


2008-11-24_173624_solid_screw--wf2--.prt.zip
 
Jeff, thanks. I thought picking up models from McMaster or Southco wouldn't be considered "stray junk". I was just on McMaster looking for the part I needed and they had a model so I grabbed it because it wasn't already in our library.
 
Well, sometime you have to settle for what you can get. Vendor parts, etc. Try
different formats if you have problems with one or the other. STEP should be
the most reliable bet because most developers (and vendor 'automated' modelers)
usually have their STEP library interfaces worked out. IGES less often.
Something like, for instance, Solidworks writing Pro/E or Granite ~~~ maybe.


There are a lot of good reasons to look for or build your own table driven
parts, not the least of which is the author probably didn't waste time modeling
unnecessary detail like cut threads and if they did you can relatively easily
delete or suppress features. It will also save you the expense of opening an
account with a model patcherupper.
smiley2.gif
 
Even with the bad surfaces, the SouthCo downloads are better than building it yourself. I get the impression that they use Pro|E and simply don't want to share their native files. So they export as a neutral and re-import into Pro|E, and share that as a 'native' Pro|E file.

Screws and stuff, sure, it may make sense to build your own library. The SouthCo stuff is a lot more complicated than a screw.
 
"Even with the bad surfaces, the SouthCo downloads are better than
building it yourself. I get the impression that they use Pro|E and
simply don't want to share their native files. So they export as a
neutral and re-import into Pro|E, and share that as a 'native' Pro|E file."


I wasn't really suggesting modeling items like the hinge.


Your guess is as good as mine but those don't look like Pro/E surfs.
Their IGES is written out of Solidworks (doesn't look like that either).
Their STEP is out of I-DEAS (I might guess that).


The IGES imported with about as many problems as the Granite neutral / 'native'.
The STEP was a no fault import.
 
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