missing cross section

[mudassirkhan]

Dear friends,
I am trying to create a cross section named A in the assembly. But Pro/e gives warning that the cross section having name A already exists. I have searched in the assembly and also in the drawing but there is no cross section named A. Pls help me solve this problem.

 

[deepakbhat_nie]

Hi,


Open the part or the asm of the view in which you are trying to create the c/s.in view<view manager click on x section.you will see a section by name 'A' delete it or redifine it.If you delete it you can create another c/s in the name'a' if you redifine it you can use the same in drawing to create the c/s.


Regards,


Deepak Bhat

 

[mudassirkhan]

Dear deepak,


Thats where the problem is. There is no section named A in the view manager.

 

[deepakbhat_nie]

Hi,


In drawing rmb on the view click on properties.In section<2d c/s click on + button do you see a name 'A' along with create new??.if you see that then rmb on 'a' and rename it to something else other that A and create an new cs with A as the name.


but if you are not seeing 'A' when you click on the + button, Then something is wrong.If this is the case can you send the pic of the error and pic when you click on the+ button in section.


Regards,


Deepak Bhat

 

[miki]

Hi,
I'm having this problem too with WF3.0 but not with WF2.0.
I think that this is something about losing references of cross section.
The cross section is still there where it was created but it dissapears from the list, so it is inpossible to redifine it or delete it because I can't select it.
If someone knows how to solve this problem, please help.



Edited by: miki

 

[Pro-Grizzly]

...


If someone knows how to solve this problem, please help.

Hi, guys!


I think, I know the decision...

At least, Iconfronted with this problem often


and always successfully solved it.


So,


For example, if we have an assembly called "Total-Assy.asm"


and also we have the problem listed above with the "A" cross section.


First of all: Info -> Global Reference Viewer -> Show Reference Graph ->


Tree -> Collapse -> All.


Pick LMB the first string (Total-Assy.asm), then


- Tree -> Expand -> One


Finda string like this:


Section of an offset xsec A id 374


Close Global Reference Viewer dialog box.


Tools -> Program... ->Edit Disign


CTRL+F and type 374 -> Find


Close the Dialog. You can see something like this:


ADD FEATURE (initial number 72)
INTERNAL FEATURE ID 374
FEATURE WAS CREATED IN ASSEMBLY 1891-0268_SBORKA-FORMI
PARENTS = 39(#7) 44(#8) 62(#10) 22(#9) 67(#11) 73(#12) 86(#14)
TYPE = COSMETIC


SECTION NAME = S2D0001



ATTRIBUTE: NO DISP
FEATURE'S DIMENSIONS:
d92 = 334.011 General_Dims (weak)
d93 = 130.854 General_Dims (weak)
d94 = 33.089 General_Dims (weak)
END ADD


DELETE that ALL!!!


Leave ONLY two empty strings betweenstayed blocks!


File -> Exit -> Save the changes


Regenerate the File (Agree with "Yes").


Thats all...


*Also bofore above activities you could check,


if the Total-Assy.als file is in the directory -- Delete it.


Tnx for the attention!
Edited by: Pro-Grizzly

 

[miki]

Hi Pro-Grizzly,
Thanks for your answer.
I'll try to solve the problem this way.

 

[bobb]

I've run into this same problem. I put a part on a drawing with section views. I did a 'save-as' to creat a similar part.Itsaved the secion names with the new part. I tried the above answers but can't seem to delete the unused section names so that they can be re-used on the new drawing.


Any help would be appreciated. (I'm running Wildfire)


Thanks

 

[bobb]

I found it! Double click on an x-sec. Click on x-section on the modify menu. Clickdelete on the drop down menu and the sec names appear. Click on the ones you want to delete and they go away!!!


I saw this earlier but thought it would delete the view, which I didn't want to do.I tried it anyway after saving my drawing in case it didn't work.


bobb