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pattern using curve

are you in the fill pattern type sub type curve. if so you can only use 2D/planar curves. If you are in the curve pattern type then you should be able to pick any 3d curve that doesnt have non-tangencies.
 
csusie said:
are you in the fill pattern type sub type curve. if so you can only use 2D/planar curves. If you are in the curve pattern type then you should be able to pick any 3d curve that doesnt have non-tangencies.
Click to expand...


Where is the sub type curve and where is the curve pattern type?


what i did was that i clicked the extruded cut feature, right mouse click and select PATTERN. On the bottom left window, there is DIMENSION, DIRECTION, FILL, AXIS, TABLE, CURVE. I selected CURVE, but i cannot pick the curve that i made using intersection of 2 curves (to make the 3d curves)....
 
Hi Alvin,


When patterning using a curve, you can only pattern along a sketched curve i.e. a 2D curve.


Regards,
Shankar
 
shankar_me said:
Hi Alvin,


When patterning using a curve, you can only pattern along a sketched curve i.e. a 2D curve.


Regards,
Shankar
Click to expand...





I remember that earlier versions of WF 3.0 you could.
Edited by: csusie
 
alvin164 said:
csusie said:
are you in the fill pattern type sub type curve. if so you can only use 2D/planar curves. If you are in the curve pattern type then you should be able to pick any 3d curve that doesnt have non-tangencies.
Click to expand...


Where is the sub type curve and where is the curve pattern type?


what i did was that i clicked the extruded cut feature, right mouse click and select PATTERN. On the bottom left window, there is DIMENSION, DIRECTION, FILL, AXIS, TABLE, CURVE. I selected CURVE, but i cannot pick the curve that i made using intersection of 2 curves (to make the 3d curves)....
Click to expand...





If you use the FILL pattern type, it has subtypes/arrangements, one of them happens to be curve, but the FILL pattern can only use 2D skecthed curves. The CURVE pattern type can use 2D or 3D curves, at least it did at one point





You could always resort to patterning a datum point along the 3D curve using a DIMESION pattern and then referencing that datum point in the geometry you want to pattern along the curve
Edited by: csusie
 
Hi Susie,


csusie said:
shankar_me said:
Hi Alvin,


When patterning using a curve, you can only pattern along a sketched curve i.e. a 2D curve.


Regards,
Shankar
Click to expand...





I remember that earlier versions of WF 3.0 you could.
Click to expand...


Bellow is the image of the dash board that I get when I select curve pattern.





Proe allows me to select only 2D sketch. Is there any option to make proe to allow me to select 3D curve?


Regards,
Shankar
 
Take this as an example.
Here is a curve wound on a cylinder (pipe) and projections patterned in such a way that the projections are normal to the pipe.
In the example the curve has been wound using the WRAP command.
Let us say you need 5 instances in the pattern meaning 4 pitches.
Create a point pnt0 on the curve at 0.1 ratio.
NOTE: pnt0 is the mother point and all features requiring reference pattern should be referenced to pnt0.
Pattern this point at an increment of 0.2 (0.2*4+0.1+0.1 = 1)
To create a feature at point pnt0, we need a plane.
Create a Datum plane thru point PNT0 and TANGENT to the Pipe surface.
Select the pnt0 as SKETCH REFERENCE.
Create your feature.
Group the feature along with the Datum plane. Now pattern as a REFERENCE Pattern.
You may also refer to the following link.
http://www.youtube.com/watch?v=i5t4xSk06_w
cannot upload a picture. this site is under maintenance.
 
Hi Srinivasaniyer1,


were u able to make the 3D pattern for my tube here [url]http://www.mcadcentral.com/proe/forum/forum_posts.asp?TID=36 325&KW=alvin164[/url]??? i still can't create the pattern of the cut...


do u have any other video on youtube? this one that you showerd me is a little small...thanks


SRINIVASANIYER1 said:
Take this as an example.
Here is a curve wound on a cylinder (pipe) and projections patterned in such a way that the projections are normal to the pipe.
In the example the curve has been wound using the WRAP command.
Let us say you need 5 instances in the pattern meaning 4 pitches.
Create a point pnt0 on the curve at 0.1 ratio.
NOTE: pnt0 is the mother point and all features requiring reference pattern should be referenced to pnt0.
Pattern this point at an increment of 0.2 (0.2*4+0.1+0.1 = 1)
To create a feature at point pnt0, we need a plane.
Create a Datum plane thru point PNT0 and TANGENT to the Pipe surface.
Select the pnt0 as SKETCH REFERENCE.
Create your feature.
Group the feature along with the Datum plane. Now pattern as a REFERENCE Pattern.
You may also refer to the following link.
http://www.youtube.com/watch?v=i5t4xSk06_w
cannot upload a picture. this site is under maintenance.
Click to expand...
 
Dear alvin164,


Here try this. I received your neutral file. However, could not see how you have created the pipe and the cut.


I have tried to create an example for your study. Good luck. I have already sent a zip file to your mail id.
 
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