Profiling Text

[Kemangan]

What I would like to do is make an extruded cut of Text on a parton a cyllindrical surface but maintains the same depth from the said surface. Can someone give me some insight? I don't know if it helps but here is a profile view of the part. I marked the area where the text is to go.


View attachment 4222

 

[[-Skint-]]

Hi Kevin,


Havea read through this thread, it will point you into the right direction. A few of us active members had fun with this one, others like Me, learnt quite a bit

[url]http://www.mcadcentral.com/proe/forum/forum_posts.asp?TID=30 179&KW=offset+text+normal+to+surface [/url]

 

[kirancitd]

I Know two ways of doing it


1. create the sketch (Curve)in the view plane and project it on the surface. Then selct the surface geometrywhere you want the text --edit/ copy/ paste. Select the pasted surface go to edit trim select projected curve. now selct the trimmed surface go to edit thicken flip it and cut it.


2. create the sketch (Curve)in the view plane. Then select the surface geometrywhere you want the text to be engraved go to edit offset in offset featureset offset by feature option active there you can create sketch in the sketcher mode create the text using useedge option since text tool is turned off for this feature exit the sketcher now you will get embossing of the text then flip it cut will come automatically.


Hope you will understand thisone.

 

[Kemangan]

I got as far as projecting the Text on the surface but am at a loss when it comes to the actual "removal" (to a specified depth) of the material. Can anyone give me a tip?


View attachment 4229

 

[michaelpaul]

I got as far as projecting the Text on the surface but am at a loss when it comes to the actual "removal" (to a specified depth) of the material. Can anyone give me a tip?

One way is to create a surface offset the distance you want the text to
be engraved. Then, cut up to surface and select the offset surface. you don't need to project the text onto the surface with this method.





View attachment 4230







2007-09-28_111724_prt0001.prt.zip
Edited by: michaelpaul

 

[Kemangan]

Yes, though I still had issues removing the material. I created a "false" surface underneath in an attempt to extrude to the next surface but I still had a hard time with it.

 

[mjcole_ptc]

For this cut I did my sketch on the Front plane and created an
extruded cut Thru All in first direction and Upto Reference (Thru
Selected) in the second direction and picked my offset surface shown in
yellow as the reference.

The result is shown in second picture.
View attachment 4249

View attachment 4250

Michael


Edited by: mjcole_ptc