Strange part connection

[JamesM]

We are using Wildfire 2.0 and Intralink 3.3. I'm having a problem that makes no sense. I have a part that I'll call Part A, which is used in only one assembly, which I'll call Assembly A. I now want to use Part A in Assembly B, but when I try to check out the .prt file, Intralink also wants to check out the entire contents of Assembly C, which consists of over 1600 parts. The same thing happens if I attempt to modify the part in Intralink - it carries those other 1600 parts with it. I have no idea how this happened, and don't know of a way to 'link' a single part to an assembly like that. The only connection between Part A and Assembly C is that, at one time, Part A was a component of Assembly C, and it was removed using 'Replace'. By using the 'where used' function in Intralink, I've verified that Part A is only a component in Assembly A now. Any ideas?

 

[looslib]

Did you create Part A while in context of Assembly C? Are there any references bewteen Assembly C and Part A, such as trim curves, etc?

 

[JamesM]

There isno connection that I'm aware of. I didn't create the original part or assembly, but don't see any referencesbetween them.

 

[AHA-D]

Clicking one face on any part of the assembly C as a reference while sketching in part A is all that it takes to tie things together. Moving C entirely out of view (and memory) and then opening part A will reveal at what point the assy is needed. If you're lucky ProE will suggest to break the link.


A

 

[vlad1979]

from my experience and I work with Intralink day by day:


That part of yours has external references to the assy, at one time someone redefined let say a protrusion and it gave it references in the assy.


Even if you deleted the part from the assembly the references are still there (in the part) .


When using "where used" Intralink will give you only the assy where a part is used.


If you suspect a part has external references to a assembly you can do a "locate" for the part then select it and go to report / relationships/ report. Unselect "show all levels" and hit the update button. Now it will show you only the assy where it has references.


Now to find out which feature is related to the assy, open the part, in model tree right-click on the part name, then info/global ref viewer and in the window that will apear it will show the feature.

 

[Jacoolo]

use Global reference viewer to check all external refrences for this part
also I assume(it was and worked fine in PDMLINK 7.0) you should have on detail page for this part following option - where used and referenced by

So in PDMLINK 7.0 you got exact info what and where, even if model was stored(saved) in Workspace


however in PDMLINK 8.0 this not work - Workspace references. It starts to work after Upload.

 

[JamesM]

Thanks to those who replied. That was exactly what happened - the part referenced other features in the assembly. It's not something I've done when modeling parts, and didn't think of it.