Cross-Sectional view

[Mi_Pot]

Hi there,

I have been asked to produce a drawing of a component in which the main body is effectively sliced whils leaving other parts in tact. I have done this by creating a cross sectional view and then choosing to excluse certain parts, however when it comes to shading cut faces the hatching overlaps with uncut parts. Is there any way to stop Pro/E doing this?

 

[Jacoolo]

send pic for more details

 

[Mi_Pot]

See here for a print screen of what I mean

 

[nagabhaskar_m]

Question is not clear man

 

[Jacoolo]

question is clear with the pic

mi-pot wants to have no hatching for x-section on exluded parts, for example on the shaft

and you can see that there is hatching displayed through the shaft, but without boundry


mi-pot, as far as I know this is the general problem with pro\e that you can not manage the display of hatching in the way you want

I know it is stupid, but it is like that unfortunately((
so there is only way to work around - make a cosmetic for each part with hatching by first making interst curve and than use it in sketcher by use edge>loop

the cosmetics are nice because they are generaly hidden by solid geom, so in the end it should look as you want

but i give you no promise, I did not check that))

 

[contour]

IN "DRAWING OPTIONS" SET def_xhatch_break_around_text TO YES


MAKE NOTE WITHOUT TEXT ( ONLY SPACES)


PLACE NOTE OVER THE HATCH TO BE HIDDEN


RELATE NOTE TO VIEW


ADJUST SIZE OF NOTE BY ADDIG/REMOVING SPACES AND LINES AN BY


MODIFYING def_xhatch_break_margin_size IN "DRAWING OPTIONS"

 

[dr_gallup]

Now that is what I call a work a round!

 

[Mi_Pot]

Thanks for the suggestions chaps - it seems as though what I thought would be a fairly routine presentation is going to require more work than it needs to...

 

[Jacoolo]

and that is why I like Pro\E

you have to "feel" this software to know how to play with it

not just "click" here and it works - in Pro\E you need a little magic))))

 

[Mi_Pot]

It also makes it a pain at times!

What do you mean by 'create an interst curve' in the post above? I have tried using cosmetic sketch but I don't seem to be able to choose the right lines for the loop as it won't select the cut surface.

 

[Jacoolo]

ok, first you must create cosmetic in each part, and in part level, not in assembly

it is like that because the cosmetic is only feature which allows you to hatch(in the past it was also possible with sketched curve, but...it is past now)

but, making the cosmetic to whole boundary of comlicated part could be painfull so you can make it easier by making first a curve which is made by intersection between all surfaces(solid surfaces) and datum plane(which normaly you use for x-section)

so this option is available in Edit>Intersect, but first you have to pick solid surfaces and datum plane

so after you create such a curve You can simply create a cosmetic by use edge> loop and picking that curve

this method you can also use for creating x-section through the rib by without rib, but that is another story

 

[Mi_Pot]

Lovely

Edited by: Mi_Pot

 

[pmack009]

What about adjusting the hatch spacing until the hatch lines disappears?<?:namespace prefix = o ns = "urn:schemas-microsoft-comfficeffice" />

 

[Mi_Pot]

That's a solution to get rid of the lines completely in a cross-sectional view, however I wanted the cut face to be shaded.